Make a Part Catalogue with Inventor iPart Feature

In broad definition, catalogue is a method of item framing. It contains information or particular information, which created systematically. It can be in alphabetic or in other logic order. Catalogue usually found in companies that have various product with different dimensions. That catalogue is one of tool for people to ease delivery of product variety in marketing.


The catalogue usually contain important information of displayed products. Those information can be dimensions, article’s number, type of material, etc. Those information usually displayed in a table so they look unique between one to each other.

For accommodating making catalogue need, Autodesk Inventor provide a feature called iPart. With iPart we can make parts with same shape but have different dimensions. According to Autodesk, iPart feature has function to transform a single part into a table driven part factory so each table row in a table driven part creates a unique part and can configure a row independently. After all information filled into iPart table, then those information are ready to be created into catalogue table. To know detail of catalogue making using iPart feature, follow below instructions.

A.    Make a Model

a1.    Use “Standard (mm).ipt, make sketch with dimension properties as following picture.

cone sketch

To make dimension properties like sketch above, we can do it by typing name and value in dimension we made. Look at picture below.

edit dimension window

a2.    Click “Revolve” on “Create” panel in “3D model” tab. Revolve dialog box will show, then choose sketch available as profile and Z axis as revolve axis.

revolved conical reducer

a3.    Save the file with name “Conical Reducer”.

B.    Make Custom Properties Model

b1.    Right click at “Conical Reducer” in Model Browser and select “iProperties”, so “iProperties” dialog box will be shown.

iProperties dialog box

b2.    Select “Custom” tab, then enter “Article Number” on “Name” column and select “Text” for “Type”.

C.    Make iPart Model

c1.    Click “Create iPart” on “Author” panel in “Manage” tab, so “iPart Author” dialog box will be shown.

iPart Author window

c2.    Delete all column in iPart table except Member column and Part Number column.

c3.    Select “Parameters” tab and click at “Angle” parameter then select arrow sign between “Name” column and “Parameters” column. So, “Angle” parameter will be shown in “Name” column and iPart table. Do same step for “Height”, “Diameter” and “Thickness” parameter, so all parameter will be shown in iPart table.

adding parameters to iPart table

c4.    Select “Properties” tab, expand “Custom” folder and click at “Article Number” properties then select arrow sign between “Name” column and “Properties” column. So, “Article Number” properties will be shown in “Name” column and iPart table.

c5.    Fill iPart table with the information like picture below :

conical reducer table

To add row in iPart table, you can right click at the first row and then select “Insert Row”.

c6.    Click “OK” to save iPart table.

c7.    Expand “Table” in Model Browser, select all items in it then right click at one of items then select “Generate Files”.

generating iPart files

D.    Make a Part Catalogue in Drawing

d1.    Make drawing with ISO standard like picture below :

iPart drawings

d2.    Click “General” on “Table” panel in “Annotate” tab, so “Table” dialog box will be shown, then select “By Standard Table (ISO)“ on “Format” panel in same tab.

iPart table for drawing

d3.    Click “Select View” button for the source, then select “Top View” of part in the drawing. And “Table” dialog box will be shown like this.

view selection for iPart table

d4.    Click “Column Chooser” button for Column and Rows, and “Table Column Chooser” dialog box will be shown.

table column chooser

d5.    Delete “Member” from “Selected Columns” and add “Part Number”, “Angle”, “Height” “Diameter”, “Thickness”, and “Article Number” to “Selected Columns”.


Click “OK” to save the changes.

d6.    Click “OK” in “Table” dialog box to apply the changes.

d7.    Place the table beside part drawing and the result will be like this picture.

finished part catalog

And now you have a part catalogue for Conical Reducer.

This tutorial only explain how to make a simple part catalogue, but I think you can develop better than me for complicated part. For the next, maybe you need better layout for the part catalogue. You can export this table to Excel file and part drawing to image file format if you want.

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  1. says

    These are great Andriana  – have you ever thought of using Chronicle to record these and post/embed on your blog? 

    Best – Eric Stover / Autodesk